In a Pro/ENGINEER drawing, an assembly drawing format can be modified so the BOM Report Table reflects multiple configurations of an assembly. This can be based either on family table instances or separate assemblies.
The following technique shows how to create additional columns in a table to reflect the multiple configurations:
· Open an assembly drawing format and zoom in on the BOM Table.
· Edit the BOM Table to add a column or multiple columns if multiple configurations are needed. If a quantity column already exists, add the new columns adjacent to the existing quantity column. Select Table > Insert > Column and select a location on the existing table (see Figure 1).
· On the top or bottom row of the new column, depending on whether the table is ascending or descending, add text describing the configuration (-11, -21, -31, etc.) (see Figure 2).
· Select the block in the column by clicking the right mouse button and selecting Properties. Enter the desired text. Select OK on the Note Properties window (see Figure 3).
· On the next row, up or down, add a report symbol that defines the information populating the column (see Figure 4).
· Select the block in the column, click the right mouse button, and select Properties. Select Report Symbol and then select RPT and QTY from the tables displayed. Select OK on the Note Properties window (see Figure 5).
Use Repeat Region Switch Dims to see the report symbols in the table.
· To complete the column, select Table > Repeat Region and Column Model/Rep (see Figure 6).
· Select the block in the new column of the table that contains RPT.QTY (see Figure 7).
· The system will prompt you to browse for and select the instance of the assembly or new assembly to be represented by this column (see Figure 8). Select Confirm.
Was this tip helpful? Let us know.